//    ----------------------------------------
//    
//    The following SmartCAM code generator has been 
//    created to generate NC code for the respective 
//    machine and control combinations listed below. 
//    
//    Due to differences in programming styles, 
//    controller versions, and optional equipment, 
//    SmartCAMcnc DOES NOT and CANNOT guarantee
//    that the NC code generated is correct for any 
//    specific machine. Some modification to the code 
//    generator to match your setup and output 
//    requirements is likely necessary. 
//    
//    Modifications to code generators do not TYPICALLY
//    require a significant amount of time. SmartCAM 
//    customers with active SMA contracts are entitled 
//    to support for their code generators from the 
//    SmartCAMcnc Support Group. To contact them for 
//    support, please send an email to: 
//    Support@SmartCAMcnc.com. If you would like 
//    information on purchasing SMA for your SmartCAM 
//    products, please contact: Sales@SmartCAMcnc.com
//    
//    DISCLAIMER: It is the responsibility of the end 
//    user to confirm and verify that the NC code 
//    created by any code generator is accurate and 
//    will not cause a machine malfunction which 
//    could result in stock, tooling, machine, and/or 
//    personal injury. 
//    
//    SmartCAMcnc assumes no responsibility or 
//    liability for any damage caused or alleged to 
//    have been caused by the use of any of the code 
//    generators it provides.
//    ----------------------------------------

@COMMENTS

M3.NTS														08/15/90

Machine: Bridgeport Vertical Mill

Control: Boss 3

Machine File Name: M3.SMF

Template File Name: M3.TMP

Tape-to-Shape File Name: Not Applicable

Notes:

	1. This machine and template file have been set up to support the
	   following fixed cycles:

			G80 - Fixed Cycle Cancel
			G81 - Drill Cycle
			G82 - Spot Drill with Dwell Cycle
			G87 - Chip Breaking Drill Cycle *
			G83 - Deep Hole Drill Cycle *
			G84 - Tapping Cycle
			G86 - Boring Cycle
					* (See Note #3)

	2. Speeds in the Job Plan should be specified in revolutions 
	   per minute (RPM).  Feeds should be in inches per minute (IPM).
	   In order to produce code which will turn the spindle in a reverse
	   direction, type the spindle speed in Job Plan as a minus number.
     
	3. SmartCAM will automatically ouptut a G87 peck drill cycle, assigning
	   the first "Z" value to equal the total depth of the hole, the second
	   "Z" depth to equal 1.5 times the drill diameter, and the third "Z"
	   value to equal the drill diameter.  To change the default setting to
	   G83, assign #U1=83 in the tool comment line of the desired tool in
	   Job_Plan.  The "U" must be a capital letter and must be preceeded by
	   the "#" symbol.  G83 will then remain in effect until the statement
	   #U1=0 is entered.  The values of the second and third "Z" inputs can
	   also be changed in the tool comment line.  #V1 is used to set the
	   second "Z", and #V2 is used to set the third "Z".  They also must be
	   capital letter preceeded by the "#" symbol, and will remain in effect
	   until another value is input.  A value of "0" will cause the default
	   values to be output in all cases.


@START
%N01 #ABSI #MOV X#XPOS Y#YPOS S#SPEED T#TOOL M06
#ONBLK Z#ZPOS

@TOOLCHG
#EVAL(#V0=0)
#RESET(#C0)
#UPDATE(#FXD)
 #ABSI #MOV X#XPOS Y#YPOS S#SPEED T#TOOL M06
 Z#ZPOS

@END
< #DCOMP> G90 G00 X#XHOME Y#YHOME M02
#OFFBLKE

@STPROF
< #ABSI>< #MOV>< X#XPOS>< Y#YPOS>< Z#ZPOS>

@RAP
< #ABSI>< #MOV>< X#XPOS>< Y#YPOS>< Z#ZPOS>

@LINE
< #MOV>< X#XPOS>< Y#YPOS>< Z#ZPOS>< F#FEED>

@ARC
< #MOV>< X#XPOS>< Y#YPOS> I#XCTR J#YCTR< F#FEED>

@ZCLRMV
< #FXD>< #MOV>< Z#ZPOS>

@ZCHKMV
< #MOV>< Z#ZPOS>

@ZDPTHMV
< #MOV>< Z#ZPOS>< F#FEED>

@FXD1
#IF(#V0=0)<#RESET(#XPOS,#YPOS)>
< #ABSI>< #FXD>< X#XPOS>< Y#YPOS>< Z#ZDPTH>< F#FEED>
#EVAL(#V0=1)

@FXD2
#IF(#V0=0)<#RESET(#XPOS,#YPOS)>
< #ABSI>< #FXD>< X#XPOS>< Y#YPOS>< Z#ZDPTH>< F#FEED>
#EVAL(#V0=1)

@FXD3
#IF(#V0=0)<#RESET(#XPOS,#YPOS)>
< #ABSI>< #FXD>< X#XPOS>< Y#YPOS>< Z#ZDPTH>< F#FEED>
#EVAL(#V0=1)

@FXD4
#IF(#V0=0)<#RESET(#XPOS,#YPOS)>
< #ABSI>< #FXD>< X#XPOS>< Y#YPOS>< Z#ZDPTH>< F#FEED>
#EVAL(#V0=1)

@FXD5
#IF(#V1=0)<#EVAL(#V1=#TLDIA*1.5)>
#IF(#V2=0)<#EVAL(#V2=#TLDIA)>
#IF(#U1=83)<#EVAL(#C0=1)>
#IF(#V0=0)<#RESET(#XPOS,#YPOS)>
< #ABSI>< #C0>< X#XPOS>< Y#YPOS>< Z#ZDPTH>< Z#V1>< Z#V2>< F#FEED>
#EVAL(#V0=1)
@